You are wasting valuable cycle time and not even realizing it! In today's episode, Mark explains how the peck drilling cycle you are most likely using is adding time to your programs. Using Q values is costing you money, learn how to properly use I-J-K values instead. This is one of those tips you will use in your shop literally every day, don't miss it.
Don’t miss any TIP-OF-THE-DAY videos. Click here (http://ow.ly/s28l30mTiUo) to join our email list! If you enjoyed this video, please hit the like button and share it with a friend who’ll find it helpful . . . and thanks! Follow Haas: Facebook – / haasautomati. . Instagram – / haas_automa. . Twitter – / haas_automation
AI Generated·May contain errors
Video Summary
AI Generated
This video explains how to optimize peck drilling cycles on Haas machines to reduce cycle time and tool wear. By moving from standard fixed-depth pecks (Q) to progressive pecks (IJK) or high-speed cycles (G73), operators can significantly increase efficiency, with the ultimate goal being the elimination of pecking through through-spindle coolant or advanced tooling.
Hello and welcome to this Haas tip of the day. Today we're going to talk about a great evil,
a necessary evil, one that I use every day, but an evil nonetheless. We're talking about
peck drilling. So a man was given the job of painting the white lines down the center of a
highway. Now on his first day, he painted six miles. The next day, three miles. The following
day, less than a mile. So his boss calls him into his office and says, what's going on? You
started out so great. The man looks at his feet and just says, boss, I'm trying my best. But that,
that paint can just keeps getting further and further away each day. Get it? You can press
pause. We'll wait for you. Well, we can explain this joke for you. Although author E.B. White
once said that explaining a joke is kind of like dissecting a frog. You understand it better,
but the frog dies in the process. Let's go ahead and dissect this frog or explain this joke.
So why did it take the man longer and longer each day to paint the lines on that road?
He painted six miles, then three miles, then one mile. He painted 10 miles overall worth of white
lines on the highway, but he walked way further than 10 miles. He had to go back and forth,
back and forth, back and forth, dipping his brush in that paint can to keep it wet. He made a lot
of trips. Again, our man did not walk 10 miles. He walked much further. Tyler, let's find out how far.
Grab that string and start walking. If our man had to dip his brush back in that can every 10 feet
to keep the brush wet, then over the course of those three days, he would have walked
more than 50,000 miles. That's twice around the planet. Tyler, I think we're going to need some
more string. I know this is a terrible joke, not realistic at all, but we explained it, we dissected
it, and we thoroughly killed it in the process. Now we can move on to our real topic, which is
peck drilling. We're going to show you how those multiple passes can add up on peck drilling as
well. In my machine, I've drilled a hole two and a half inches deep. I used a G83 peck drilling cycle
with a Q value of one half D. That's one half the diameter of the tool. This is a common value
that a lot of shops use without thinking about the implications. On this part, that works out
to 21 passes. Our tool has to go up and down, back up to that R plane, and back down to the
bottom of the hole 21 times. Just like our painter, we're going to go much further than our
two and a half inches. We're going to be moving our tool close to 60 inches to make this single
hole because we're using such a small Q peck value. This is really not funny. There is no
joke here. We're wasting a lot of cycle time with these small Q peck values,
but we can fix this. We've got to fix this. When we drill, much of our tool wear is happening as
the tip of the drill enters the material. So with 21 pecks, our tool is entering the workpiece 21
times. We are virtually guaranteeing that our drill is going to wear out quickly with this
many passes. When drilling, one half D is way too small for our pecks on most materials,
but how far can we go? How much can we take with those passes? Bigger? Bigger? Okay.
Typically, depending on the material, we can go three to five times the diameter of the tool
for that first peck, and then with each successive peck, we can take less and less material.
So how do we program progressively smaller pecks? We're going to use that same G83 code,
except this time we're going to use IJK pecks instead of Q pecks. Our I value is that initial
peck. How far do I want it to drill on that first pass? Our J value is how much I want to reduce
that peck by each and every time, and our K value is my minimum peck amount. What's the smallest
amount I want to drill by? Now, on my part, I'm using a quarter inch diameter drill. My D value
is 0.25. On my first peck, I'm going to take 4XD. Now, we've got a little bit of rapid plane in
there. We've got a drill point, and if you don't count that stuff, it's really more like 3XD,
but I used an I 1.0. That's four times the diameter of my tool. I reduced my pecks by 2XD
with each successive pass, so I used a J 0.5. 2XD in our case, quarter inch drill times 2.5,
and I want my minimum peck to be 1XD. That's a quarter inch drill. That's going to be K 0.25.
Now, these are okay starting values for most materials and drilling cycles. Check with your
tool supplier for the values that work best for your tools. Now, by making these changes,
we reduced the number of pecks we're taking from 21 down to 7. 21 down to 7 passes. This brought
our cycle time down from 18 seconds per hole to 9 seconds per hole. I'll say this again. By
switching from a G83 Q peck to a G83 IJK peck, we cut our cycle time for all of our drills in half.
Now, this G83 IJK cycle is also available on your Haas lathe, so if you're a lathe guy,
check it out. Save some time. We could also have used our G73 high-speed pecking cycle.
This high-speed cycle is going to drill, and it's still going to peck, but instead of retracting
all the way back to the R-plane, it's just going to back off by the amount that's set in setting 22,
usually ten thousandths of an inch. So, it backs off a little bit, and then it gets right back
into the cut. Now, you can use an IJK peck with a G73 cycle as well. People will peck drill for
all kinds of reasons. They'll use a G83 IJK if they need to clear some packed chips from their
drill, or if they need to get coolant on the tip of that drill. People will use a G73 cycle if they
need to break up some long stringy chips, or maybe turn them into little tiny chips. Of course, in a
perfect world, we would just use a TSC through spindle coolant drill to drill straight to the
bottom of that hole in one shot. It doesn't get any better than that. No pecking at all. That's
the fastest way to get there. Now, we showed you a G83 Q cycle. That took about 18 seconds. We showed
you a G83 IJK cycle. That took about nine seconds. We showed you the G73, seven seconds, and a TSC
drill running a G81 cycle that can punch this hole in just three seconds. So, we've given you lots of
tips, lots of options, lots of ways that you can drill faster. Now, I'm standing in front of a VF3 SS
machine. These SS models have faster accelerations, faster rapids, which means faster drill pecking
cycles. If you're running any volume of parts, you might want to look at an SS machine, pencil it out,
see if it makes sense for you, or even one of our DMDT drill tap machines. Those machines are just
built for speed. They're built for fast pecks. Well, I want to remind you to get rid of pecks,
if at all possible. If you've got a chance, get rid of pecks entirely. If not, use a G83 IJK peck
instead of a G83 Q peck, and give that G73 a try if you just want to break up the chips. Now, one
thing we haven't mentioned is the tool. We need you to call your tooling supplier. A lot has
happened in the last few years in regards to drill and tooling technology. They've got drills that
can drill the hole behind me with just regular flood coolant in one shot, no pecks at all,
right? Just a better flute design, high polished flutes. There are incredible drills out there.
We need you to call your tooling supplier because we want you to make money. We need you to make
money. I sound like one of those TV salesmen, and I don't even care, right? Call in the next 10
minutes and receive a free set of steak knives. Well, we want you to make money,
so thanks for letting us be a part of your success and for watching this Haas Tip of the Day.