I Cut This Baja Racing Part On A Wire EDM (Full Setup + Mastercam) | Machine Shop Talk Ep.163

Machine & Design
2 followers
3 Video Views·Nov 15, 2026
How would you cut two internal keys all the way through this steel coupling?
In this episode of MACHINE SHOP TALK, Ian Sandusky from Lakewood Machine & Tool walks us through a wire EDM job for the McMaster University Baja Racin
AI Generated·May contain errors
If you're into motorsports, you're not going to want to miss this one.
We just had the opportunity to do some components
for the McMaster University
Baja Racing Team. They build their own touring trucks,
design everything, get the parts machined,
machine what they can, assemble them,
and then race them against other universities.
And today we're going to be going through
a quick wire job that we did for them,
how we fixed it, how we set it up as part of that powertrain component.
But before we do, make sure you like, subscribe,
Turn on notifications below
to make sure you never miss a video. Let's get into it.
Okay guys, so as promised today, this is going
to be a little bit of a machining vlog.
I hope this is interesting.
It's also going to be a small instructional on wire EDM.
If you were trying to learn wire EDM,
I highly recommend you check out the Learn to Burn series
here on Practical Machinist with Ron.
He's fantastic. Very, very good wire shop.
This may not be as advanced as that,
but I'm going to show you how we run this job.
so this is some kind of coupling for a powertrain
that goes inside the engine or powertrain again
i'm not really a car guy
for the McMaster University Baja Racing Team so they designed
this part um they turned one we actually turned another one
that i'm going to show you with so
this is 4340 steel it's going
to get welded into position when it's done
but when we go upstairs we'll take
a look at the computer and you'll see
they basically designed this to have two internal keys
that run the entire way
through the part and they did that because when we were talking to them
i said we had a wire edm so this is not going
to be something you would ever design if you
probably don't have a wire edm or some very very fancy live tooling
but in this case it works fine
because we talked about it first
so first of all i'm going to show you how we fixtured this thing
and what we did to be able to hold it in the wire edm
So if you've seen our shop tour
or you follow us on Instagram at Lakewood Machine you'll know
that we keep pretty much every fixture we've ever made in the shop
because it's funny
not only how often will you do a job again five years later
that you thought was a one-off
but also how often you can repurpose fixtures for other jobs
so this originally was a fixture for a
actually was two fixtures mainly meant for doing keys
and internal features so you can see on this
side we were locating off the bore you can see
on this side we were locating off an existing keyway
to do something in the bore i honestly don't
really remember what part this was for it says
It says sprocket flange.
But it's been sitting on my shelf here for a while.
So for this component, you got to remember in wire EDM,
you need to be able to hold your entire cut area
out over the cut area of the table.
So nothing here.
You got to be far enough away
that those nozzles can get within range of your part.
So for this one, I already have a hole in it.
This used to be used for the wire machine.
So I know my wire EDM machine screws fit through it.
So we're one step of the way there.
Next, this already had a bore in it.
So all I did is I set this up on the wire machine.
I didn't film it because it wasn't terribly
exciting, but I picked up the bore that was there,
which was about probably inch and a half,
and I opened it up to the outer diameter of our component.
So now when I take this component,
you can see we have a nice shoulder here
on this part. I can drop it in.
It is a close fit. There we go.
And it's going to sit right on that shoulder like that.
And the nice thing about it too
is in the wire EDM you cannot have your part below the surface of
your component. I actually think it fits in this way.
Ah there it is. Fits like that. So you can see
that our part does not sit below the bottom of the fixture.
That's because your top nozzle you
can move up and down wherever you want.
Your bottom nozzle, at least in this machine, is fixed.
So if your part is hanging below the table you got a problem.
You're going to run into it.
so then all i did is i went
and tapped a hole in the side of this so now when i tighten this up
very gently we don't want to crush the part
and mar it that part's going to be held in the vise
the one nice thing about in the vise in the fixture
the one nice thing about wire edm is that
it basically has zero cutting force you have
the force of water pressure but it's not much it's
just for flushing it's not like water jet
or something so essentially as long as you can hold
it still
flat and it's not going to move on its own,
you're generally good to go. You want to make
it as secure as possible,
but fixturing is a little less low intensity than on something
like a mill. So what we're going to do now,
we're going to tighten that down. I'm going to put that
on my table. Let's go upstairs
and take a look at the program for this one. Okay. So here's what
Here's what we got, guys.
This is the internal of that bore.
So when we turn this,
we basically turned it to a size where when I go to cut these keyways,
we still have room. Pretty straightforward.
So we made the bore undersized. Now,
since we're only doing the internal part of this,
we only needed the internal geometry
here to be able to work from.
So the amazing students at McMaster University, I believe Spencer
put this one together. You can see
that we're using SOLIDWORKS. So that's just fine. This is
Just for instructional use,
what they did is they designed this profile.
So when we program something in wire,
the first thing you need to do is have a thread point.
So when I go in here, I'm going to go to wireframe, point position.
Now a thread point is going to be where your wire goes to thread.
Now you can have 10 million thread points on your page
and you can use them all.
If you wanted to, you could have 10 million
thread points and not use any of them.
It only becomes part of the program when you select it with a chain.
But easy enough, we know we want
a thread point right here in the center of my part,
and that's also going to be my zero.
So what we're going to do is we're going to put that
fixture on, secure our part,
then we're going to go and pick up the center of that bore. So
right there, I'm also going to thread right
in the center of the bore. Easy peasy. The next
thing we want to do is select our chains.
So much like if you have programmed in a CNC mill,
If you're using Mastercam, it's the only one I know that does wire.
I don't know any other wire programs you could use,
but you were going to select your chains
just like selecting a contour with a mill.
Pretty simple.
It's simple.
The one thing we always say is when you think of wire,
think fancy bandsaw.
Everything's going to be straight or it's going to be on an angle.
I mean, there's a lot more to it than that.
But anyway, so let's select our chains.
I'm going to reselect these for you
so you can see what we're doing here.
Rechain all.
So the first chain I want to select.
You always select your thread point.
So that's going to tell it for this next chain,
I want you to use this thread point.
That's only really important when you have multiple thread points,
but you have to do it anyway.
So I've selected my thread point.
Next, I'm going to select the chain
and tell it what side of the line I want it to go on.
So I want this to start on the flat, because since it's going
to be a flat, it's something that after I cut the tab out,
if there's any kind of little remainder there,
we can just file it out or we can skim it off.
Again, you can run a skim pass after.
There's a lot of ways to do this.
This I know is going to work pretty well because I've already done it.
But what we're going to do is going to select that chain right there.
So you can see that green is where it's going to start.
And right now it's not showing me what side of the line.
So let's say OK.
Okay, and you can see.
It's going to cut this direction,
and it's going to cut on this side of the line,
which is what we want. Much like when you have a cutter,
you don't want the cutter on the wrong
side of the geometry or you're going to cut too much.
It's the same thing with wire. Even though
it's 10 thou, if you put it on the wrong side,
that part's going to be completely out of spec.
So that is correct. If I wanted to reverse that, you can.
I would just right click. You can either
I'm going to either hit change side or change.
You can either hit change side or you can reverse it.
So reversing, reverses the direction and also changes the side.
Generally, you don't care what direction
you're cutting as long as the side is right,
but we want to make sure it is on the right side there.
So great, we've got that selected.
Next, we're going to go into our parameters.
So there are many, many, many parameters in Wire EDM.
We are going to stick to the most basic
because generally 90% of the time,
you don't need to touch many things in here,
especially not the power parameters or...
Anyways, we'll get into it.
So wire power, I'm going to leave this all the same.
The way I program this, because it's just
the way I've always done it, we have a 10 thou wire,
which has one thou overburn per side. So
if you took a straight cut through material,
it would be a 12 thou slot. So I have my diameter set
to 12 thou. It's because I've used this post
and the way it's been working for probably 15 years
now, if not more. You may want to actually adjust your overburn here.
I know this works on my
machine, so this is how I'm going to do it.
Next, I'm going to go to my cut parameters.
So there are a few things in here that I want to do.
I want to perform a rough cut. So your rough
cut is going to be your first cut.
For a lot of applications, this is going to be good enough.
If you're getting into the tenths,
if you're getting into really tight tolerance stuff,
you're probably going to want to rough and then skim.
The one choice you have is do you want to
skim before you cut a tab?
So what a tab is, is let's say I have a part and it's sitting in a big
When I cut it out, if I just went and cut it,
that part's going to drop out and all of a sudden
it's going to jam up my machine.
So what the machine automatically does is it can leave a
tab. So it's going to cut to within 30 thou at the end of that cut
and wait for me. It's going to
stop. Then when I go press the green button,
make it go, it's going to cut the remainder of it.
I hear it drop. I stop it. I pull it. Very, very common.
You can leave all your tabs to the end
so it runs overnight and come in and
cut your tabs. You're done. And so on.
We do want to use a tab on this one.
I'm going to use a 20 thou tab. The reason I chose that
is just because of the way the lead-in, lead-outs work on this.
I don't have a lot of room for a
tab. I'm going to leave a 20 thou tab.
It's going to be enough because it's just to hold it while
it finishes that cut. Number of tab cuts is one because I want it to.
I do want to make the tab
cut-off move with a skim cut.
This is because I'm only doing one cut. I just want it to go around,
cut it, and then go into the skim.
Again, you will probably never need to do this if it's
I want my skim cuts after the tab.
So after I go and I cut off that tab, I want it to go
skim the entire thing again.
So that's going to get rid of that little tab that might be left,
any debris. It's also going to make sure
that everything is super, super accurate.
Because when you're cutting your first cut,
sometimes the water can be bouncing the thing
around a little bit, the wire around a little bit.
Sometimes it might get a little jammed up
if the slug moves. So it's always good to have
a skim if you're doing very, very particular stuff.
Make sure it is dialed in on your system
because it is a whole different set of things. But
anyways, we're going to do a skim.
My compensation, I'm going to do the compensation in this computer.
The other option you have is to do it in the control.
I always do it in the computer.
You will probably determine what works on your end.
We've already said what side of the line we want the wire on,
so we're going to keep it
that way.
And flushing, this is always important at Wire EDM.
So when it's cutting, that wire has water running along it.
So as it's eroding everything going in front of it,
it's flushing all that debris out of
there.
If that debris builds up, you've got a problem
and it's going to break your wire.
We just want flushing on.
That's it.
Sweet.
Okay.
And just like that, you can see we have our wire path.
You can see that's where our tab is and that's where
our little lead in lead out is going
to be.
So now I know this is good.
We're going to post it just like that.
We're going to put it on our floppy disk
because I have a very old machine but these programs are
very small and let's go down to the machine and run this one off.
Okay so we're going to want to
first make sure our part is nice and tight in the fixture.
I'm just very lightly tightening that.
We don't want to mar the surface we're just keeping it nice
and light but that has it in
nice and tight. Next I'm going to jog this way
because it's right in my way.
Excuse my dirty machine, I need to clean it out with muriatic acid.
But all we want to do is make sure that this component
is held out far enough over it that I'm not going to get a limit error.
You know, this thing has travels just like a CNC machine.
Because I have this round part, so it doesn't matter if it's indicated,
I'm going to kind of hang it out.
Well, I'll actually be able to hang it out like that.
So what we can do is we can actually go
and indicate this in to make sure it is good.
I actually didn't think it would be far enough there, but that's okay.
Tighten that down lightly and let's indicate this in.
So just like indicating a vice on a mill,
you're going to do basically the same thing.
I'm going to start my...
Oh, I got a socket edge there.
I have a nice milled edge on the front there.
Let's move that down
and drop my Z.
So these are all your manual feed rates.
Zero, one, two, three.
They're just different speeds that it's going to move at.
That's about it.
I'm going to walk it in and you can see we're at zero.
Boost up our speed.
And you can see this is very, very off-center.
And because of the rotation point, I know it needs to go that way.
And as always, I was a bit stupid here.
You want to make sure when you're indicating things,
you always want to start where the screw is
because that's going to be your pivot point if you're using one point.
Oh, no. Bad, bad.
And just like that, we have our part running true at zero.
Easy peasy.
So we're going to take this off.
So the next thing we want to do is find our zeros.
So I'm going to put this bring my UV back into order here.
Again, your UV.
So you got X, Y, then you got UV.
This is UV because you can move it off center.
We're going to go pick up our height right now.
We want to make sure this is nice and tight to the top of the part.
So we're going to drop that in nice and easy.
Make sure you never bump the head because it will be very angry at you.
And to make sure that is set at zero.
In my MDI here we're going to hit G97Z
and when you watch here on the Z that's going to change
to zero in my 54 offset. That's good.
Now let's set the tube height. So we hit free. This is going
to be the threading tube. So this thing threads the tube
and it needs to be within about a hundred
thou quarter inch of the bottom there.
It's not too particular but we want to make sure that
tube is either not smashing into that bottom head
or we want to make sure that it is not
Too far away because if you have
a new fancy machine they will thread with no tube if you
have an old machine like mine it needs a drop tube
to be able to thread. So we're going to feed a bit
of wire through just make sure we have a nice start.
I'm going to hit my cutter button that
cuts that little piece of wire off
and we throw it in our handy dandy trash can here. Now let's go and
pick up our bore. So we're going to kind of eyeball
the center of the bore there we're going to hit
I'm going to put it in a condition 777 for this machine
because that is our picking up setting.
Basically, it's going to run the wire
a little bit slower. It's a little more sensitive.
We don't need to be burning a ton of wire,
just picking something up here.
And you can see it kind of failed to thread
on the first time there. That's okay. It's
going to automatically retry.
And just like that, we are in the hole and we are good to go.
So I'm going to jog this up just so you guys can see here.
So I'm just going to eyeball the center
of this hole keeping it in condition 777. We're going to
go to codeless. Now I always say the wire machines
are essentially the original probes because it
will pick up its own. So to pick up
the hole center we're going to click the hole center button.
Pretty easy. Our feed amount,
so this is how far it's going to feed before it slows down. This is
just so it doesn't take forever.
I'm going to do 1.75 because I know how big this is in both
Both directions.
Inverted value we're not going to change.
Wire diameter we're going to put to 10 thou because
that's what my wire diameter is and let's pick it up.
So it's going to go now you can see it's moving
it's going to basically go until it hits interference try it again
move back to the other side
and after it picks up all four edges of that hole much like a probe
it's going to know the exact center of that hole
and set it to zero which is what we want.
And you can see now we are at zero zero which is good.
So next let's set our water height. So what
we want is we want our water
to come up about halfway through this bolt in this machine.
Now we can close the door so we don't spill water all over the floor.
We are going to fill the tank.
It's going to get very loud now.
And I'm going to set my water height approximately but we can dial
that in after. Next take our fancy dan floppy disk pop it in.
So we want to load a program.
Load user disk. I only have one program on here which is lovely.
So we're going to pull that up.
We're going to pull our disk out so we don't forget it.
So the next thing you have to do is find
your conditions. These machines are
very handy in that they find their own cutting conditions.
It basically tells it what the power
should be, what the feed should be, the wire speed.
So we're going to tell it our cutting
fluid is water, 10 thou wire, wire material is brass.
Our workpiece is steel.
It is approximately four inches long, so we're going to go to 3.94.
It's a punch.
We are in closed cutting conditions enough.
Closed is when you are tight to the part.
Open is if you're cutting something
way far down, but the head is up here.
This technically would be open,
but it's closed enough for this machine.
So we're going to hit fine.
So this brings up all my cutting codes here.
and i know that my machine is going
to have a little bit of trouble with this
so i'm just going to manually adjust the code
a little bit here to something that i know
is going to work i'm basically just turning down
the power it means it's going to be a little
slower but it's not a big deal next thing we want to do is draw it
so we hit graphic
we want to turn on our limit check oops
so this is going to check to make sure that
it's not going to over travel anywhere
and not be able to run my part we hit draw
Oh, we hit a limit check, that is so annoying.
So what we're going to do now, we're going to move
that part and we're going to pick it up again.
And thanks to the magic of television we have
just went and picked it up and you didn't miss a thing.
So once again we have our program here
we have our conditions, we're going to hope
for the best, we're going to say draw and look at that, it's
not going to over travel anymore.
Always better to find out if it's going to over travel before
you start running it because picking it up again might
be a problem depending on what you're doing.
All looks good.
We're going to save that to our screen.
Easy peasy. Now all we do is go to run.
We're going to click the top of our program
and hit the big green button.
So now this is going to cut forever. The way we're doing this
is very slow because I want it to be accurate.
This is also an old machine. This is a 2005 I
believe. If you have a newer machine you can
do this thing in like an hour, hour and a half. This
will probably run for like six hours if we're lucky.
So now it's getting into the cut.
So when we're looking at our screen here
you can see we get quite a bit of info.
Our g-code is here just like on any other machine.
You can see our red dot there is where our wire actually is right now.
I'm actually going to make that go faster
for a second so it can actually
get into the cut. That's just the surface speed. It's
going to get angry if it bumps it.
Over here you can see what our actual
cutting speed is. It's not actually
started cutting so that's not going to
be real.
Cut perimeter is the total length of the cut
so if you take your speed or take your cut perimeter
divide it by your speed you'll be able
to figure out how long that is going to take to cut
and just like that you can see we are in the cut
so it is 7:36 in the morning right now we are
currently cutting at 17 thou per minute, we are going to come back
when this is done i'm going
to let you know what time it was how long it took
and we're going to take a look at the final part
All right, magic of television time.
So to do this slug out of that part, you know this is how it started
that's the part that came out
of it that took around seven hours
And 15 minutes, but that's also including the skim cut.
And the skim cut is basically just
to make sure everything is nice and smooth.
It's right where it needs to be.
So I hope this has been helpful, guys.
If you have any questions about wire EDM, of course, you can ask me.
Of course, check out the Learn to Burn series here
on Practical Machinist with Ron from Cam Wire.
And as always, make sure you like, subscribe,
and turn on notifications below to make sure you never miss a video.
Thank you very much for watching, guys. You take care.
